foamToEnsight.C File Reference

Translate OpenFOAM data to EnSight format. An Ensight part is created for cellZones (unzoned cells are "internalMesh") and patches. More...

Go to the source code of this file.

Detailed Description

Translate OpenFOAM data to EnSight format. An Ensight part is created for cellZones (unzoned cells are "internalMesh") and patches.

Original source file foamToEnsight.C

• Handles volume fields, dimensioned fields, point fields
• Handles mesh topology changes.

Usage

foamToEnsight [OPTION]

Options:

• -ascii

  Write Ensight data in ASCII format instead of "C Binary"

• -fields <fields>

  Specify single or multiple fields to write (all by default) For example,

        -fields T
        -fields '(p T U \"alpha.*\")'

  The quoting is required to avoid shell expansions and to pass the information as a single argument.

• -nearCellValue

  Use zero-gradient cell values on patches

• -nodeValues

  Force interpolation of values to nodes

• -no-boundary

  Suppress output for all boundary patches

• -no-internal

  Suppress output for internal (volume) mesh

• -no-cellZones

  Suppress cellZone handling

• -no-lagrangian

  Suppress writing lagrangian positions and fields.

• -no-mesh

  Suppress writing the geometry. Can be useful for converting partial results for a static geometry.

• -no-point-data

  Suppress conversion of pointFields. No interpolated PointData.

• -noZero

  Exclude the often incomplete initial conditions.

• -index <start>

  Use consecutive indexing for data/######## files with the specified start index. Ignore the time index contained in the uniform/time file.

• -name <subdir>

  Define sub-directory name to use for Ensight data (default: "EnSight")

• -width <n>

  Width of Ensight data subdir (default: 8)

• -cellZones NAME | LIST

  Specify single zone or multiple cell zones (name or regex) to write

• -faceZones NAME | LIST

  Specify single zone or multiple face zones (name or regex) to write

• -patches NAME | LIST

  Specify single patch or multiple patches (name or regex) to write For example,

        -patches top
        -patches '( front \".*back\" )'

• -excludePatches NAME | LIST

  Exclude single or multiple patches (name or regex) from writing. For example,

        -excludePatches '( inlet_1 inlet_2 "proc.*" )'

Definition in file foamToEnsight.C.