This boundary condition provides a wall constraint on the specific dissipation rate, i.e. omega, and the turbulent kinetic energy production contribution, i.e. G, for low- and high-Reynolds number turbulence models. More...

Inheritance diagram for omegaWallFunctionFvPatchScalarField:

[legend]

Collaboration diagram for omegaWallFunctionFvPatchScalarField:

[legend]

Public Member Functions
	TypeName ("omegaWallFunction")

	omegaWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)

	omegaWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)

	omegaWallFunctionFvPatchScalarField (const omegaWallFunctionFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)

	omegaWallFunctionFvPatchScalarField (const omegaWallFunctionFvPatchScalarField &)

virtual tmp< fvPatchScalarField >	clone () const

	omegaWallFunctionFvPatchScalarField (const omegaWallFunctionFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const

virtual	~omegaWallFunctionFvPatchScalarField ()=default

scalarField &	G (bool init=false)

scalarField &	omega (bool init=false)

virtual void	updateCoeffs ()

virtual void	updateWeightedCoeffs (const scalarField &weights)

virtual void	manipulateMatrix (fvMatrix< scalar > &matrix)

virtual void	manipulateMatrix (fvMatrix< scalar > &matrix, const scalarField &weights)

virtual void	write (Ostream &) const

Public Member Functions inherited from fixedValueFvPatchField< scalar >
	TypeName ("fixedValue")

	fixedValueFvPatchField (const fvPatch &, const DimensionedField< scalar, volMesh > &)

	fixedValueFvPatchField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const scalar &value)

	fixedValueFvPatchField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &, const bool valueRequired=true)

	fixedValueFvPatchField (const fixedValueFvPatchField< scalar > &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)

	fixedValueFvPatchField (const fixedValueFvPatchField< scalar > &)

	fixedValueFvPatchField (const fixedValueFvPatchField< scalar > &, const DimensionedField< scalar, volMesh > &)

virtual tmp< fvPatchField< scalar > >	clone () const

virtual bool	fixesValue () const

virtual bool	assignable () const

virtual tmp< Field< scalar > >	valueInternalCoeffs (const tmp< scalarField > &) const

virtual tmp< Field< scalar > >	valueBoundaryCoeffs (const tmp< scalarField > &) const

virtual tmp< Field< scalar > >	gradientInternalCoeffs () const

virtual tmp< Field< scalar > >	gradientBoundaryCoeffs () const

virtual void	operator= (const UList< scalar > &)

virtual void	operator= (const fvPatchField< scalar > &)

virtual void	operator= (const scalar &)

virtual void	operator+= (const fvPatchField< scalar > &)

virtual void	operator+= (const Field< scalar > &)

virtual void	operator+= (const scalar &)

virtual void	operator-= (const fvPatchField< scalar > &)

virtual void	operator-= (const Field< scalar > &)

virtual void	operator-= (const scalar &)

virtual void	operator*= (const fvPatchField< scalar > &)

virtual void	operator*= (const Field< scalar > &)

virtual void	operator*= (const scalar)

virtual void	operator/= (const fvPatchField< scalar > &)

virtual void	operator/= (const Field< scalar > &)

virtual void	operator/= (const scalar)

Public Member Functions inherited from fvPatchField< scalar >
	TypeName ("fvPatchField")

	declareRunTimeSelectionTable (tmp, fvPatchField, patch,(const fvPatch &p, const DimensionedField< Type, volMesh > &iF),(p, iF))

	declareRunTimeSelectionTable (tmp, fvPatchField, patchMapper,(const fvPatchField< Type > &ptf, const fvPatch &p, const DimensionedField< Type, volMesh > &iF, const fvPatchFieldMapper &m),(dynamic_cast< const fvPatchFieldType & >(ptf), p, iF, m))

	declareRunTimeSelectionTable (tmp, fvPatchField, dictionary,(const fvPatch &p, const DimensionedField< Type, volMesh > &iF, const dictionary &dict),(p, iF, dict))

	fvPatchField (const fvPatch &, const DimensionedField< Type, volMesh > &)

	fvPatchField (const fvPatch &, const DimensionedField< Type, volMesh > &, const Type &value)

	fvPatchField (const fvPatch &, const DimensionedField< Type, volMesh > &, const word &patchType)

	fvPatchField (const fvPatch &, const DimensionedField< Type, volMesh > &, const Field< Type > &)

	fvPatchField (const fvPatch &, const DimensionedField< Type, volMesh > &, const dictionary &, const bool valueRequired=true)

	fvPatchField (const fvPatchField< Type > &, const fvPatch &, const DimensionedField< Type, volMesh > &, const fvPatchFieldMapper &)

	fvPatchField (const fvPatchField< Type > &)

	fvPatchField (const fvPatchField< Type > &, const DimensionedField< Type, volMesh > &)

virtual tmp< fvPatchField< Type > >	clone (const DimensionedField< Type, volMesh > &iF) const

Foam::tmp< Foam::fvPatchField< Type > >	NewCalculatedType (const fvPatch &p)

Foam::tmp< Foam::fvPatchField< Type > >	NewCalculatedType (const fvPatchField< Type2 > &pf)

virtual	~fvPatchField ()=default

bool	useImplicit () const noexcept

bool	useImplicit (bool on) noexcept

virtual bool	coupled () const

const objectRegistry &	db () const

const fvPatch &	patch () const

const DimensionedField< Type, volMesh > &	internalField () const

const Field< Type > &	primitiveField () const

const word &	patchType () const

word &	patchType ()

bool	updated () const

bool	manipulatedMatrix () const

virtual void	autoMap (const fvPatchFieldMapper &)

virtual void	rmap (const fvPatchField< Type > &, const labelList &)

virtual tmp< Field< Type > >	snGrad () const

virtual tmp< Field< Type > >	snGrad (const scalarField &deltaCoeffs) const

virtual tmp< Field< Type > >	patchInternalField () const

virtual void	patchInternalField (Field< Type > &) const

virtual tmp< Field< Type > >	patchNeighbourField () const

virtual void	initEvaluate (const Pstream::commsTypes commsType=Pstream::commsTypes::blocking)

virtual void	evaluate (const Pstream::commsTypes commsType=Pstream::commsTypes::blocking)

virtual tmp< Field< Type > >	valueInternalCoeffs (const tmp< Field< scalar >> &) const

virtual tmp< Field< Type > >	valueBoundaryCoeffs (const tmp< Field< scalar >> &) const

virtual tmp< Field< Type > >	gradientInternalCoeffs (const scalarField &deltaCoeffs) const

virtual tmp< Field< Type > >	gradientBoundaryCoeffs (const scalarField &deltaCoeffs) const

virtual void	manipulateMatrix (fvMatrix< Type > &matrix)

virtual void	manipulateMatrix (fvMatrix< Type > &matrix, const scalarField &weights)

virtual void	manipulateMatrix (fvMatrix< Type > &matrix, const label iMatrix, const direction cmp)

void	check (const fvPatchField< Type > &) const

virtual void	operator= (const UList< Type > &)

virtual void	operator= (const fvPatchField< Type > &)

virtual void	operator= (const Type &)

virtual void	operator+= (const fvPatchField< Type > &)

virtual void	operator+= (const Field< Type > &)

virtual void	operator+= (const Type &)

virtual void	operator-= (const fvPatchField< Type > &)

virtual void	operator-= (const Field< Type > &)

virtual void	operator-= (const Type &)

virtual void	operator== (const fvPatchField< Type > &)

virtual void	operator== (const Field< Type > &)

virtual void	operator== (const Type &)

Protected Member Functions
virtual void	setMaster ()

virtual void	createAveragingWeights ()

virtual omegaWallFunctionFvPatchScalarField &	omegaPatch (const label patchi)

virtual void	calculateTurbulenceFields (const turbulenceModel &turbulence, scalarField &G0, scalarField &omega0)

virtual void	calculate (const turbulenceModel &turbulence, const List< scalar > &cornerWeights, const fvPatch &patch, scalarField &G, scalarField &omega)

virtual label &	master ()

Protected Attributes
bool	blended_

bool	initialised_

label	master_

scalar	beta1_

scalarField	G_

scalarField	omega_

List< List< scalar > >	cornerWeights_

Static Protected Attributes
static scalar	tolerance_ = 1e-5

Additional Inherited Members
Public Types inherited from fvPatchField< scalar >
typedef fvPatch	Patch

typedef calculatedFvPatchField< Type >	Calculated

Static Public Member Functions inherited from fvPatchField< scalar >
static tmp< fvPatchField< Type > >	New (const word &, const fvPatch &, const DimensionedField< Type, volMesh > &)

static tmp< fvPatchField< Type > >	New (const word &, const word &actualPatchType, const fvPatch &, const DimensionedField< Type, volMesh > &)

static tmp< fvPatchField< Type > >	New (const fvPatchField< Type > &, const fvPatch &, const DimensionedField< Type, volMesh > &, const fvPatchFieldMapper &)

static tmp< fvPatchField< Type > >	New (const fvPatch &, const DimensionedField< Type, volMesh > &, const dictionary &)

static tmp< fvPatchField< Type > >	NewCalculatedType (const fvPatch &)

static tmp< fvPatchField< Type > >	NewCalculatedType (const fvPatchField< Type2 > &)

static const word &	calculatedType ()

Static Public Attributes inherited from fvPatchField< scalar >
static int	disallowGenericFvPatchField

Detailed Description

This boundary condition provides a wall constraint on the specific dissipation rate, i.e. omega, and the turbulent kinetic energy production contribution, i.e. G, for low- and high-Reynolds number turbulence models.

Reference:

    Binomial blending of the viscous and inertial sublayers (tag:ME):
        Menter, F., & Esch, T. (2001).
        Elements of industrial heat transfer prediction.
        In Proceedings of the 16th Brazilian Congress of Mechanical
        Engineering (COBEM), November 2001. vol. 20, p. 117-127.

    Exponential/Max blending of the viscous and inertial sublayers (tag:PH):
        Popovac, M., & Hanjalić, K. (2007).
        Compound wall treatment for RANS computation of complex
        turbulent flows and heat transfer.
        Flow, turbulence and combustion, 78(2), 177-202.
        DOI:10.1007/s10494-006-9067-x

    Tanh blending of the viscous and inertial sublayers (tag:KAS):
        Knopp, T., Alrutz, T., & Schwamborn, D. (2006).
        A grid and flow adaptive wall-function method for RANS
        turbulence modelling.
        Journal of Computational Physics, 220(1), 19-40.
        DOI:10.1016/j.jcp.2006.05.003

Usage

Example of the boundary condition specification:

<patchName>
{
    // Mandatory entries (unmodifiable)
    type            omegaWallFunction;

    // Optional entries (unmodifiable)
    beta1           0.075;
    blending        binomial2;
    n               2.0;

    // Optional (inherited) entries
    ...
}

Property	Description	Type	Req'd	Dflt
`type`	Type name: omegaWallFunction	word	yes	-
`beta1`	Model coefficient	scalar	no	0.075
`blending`	Viscous/inertial sublayer blending method	word	no	binomial2
`n`	Binomial blending exponent	scalar	no	2.0

The inherited entries are elaborated in:

Options for the blending entry:

      stepwise    | Stepwise switch (discontinuous)
      max         | Maximum value switch (discontinuous)
      binomial2   | Binomial blending (smooth) n = 2
      binomial    | Binomial blending (smooth)
      exponential | Exponential blending (smooth)
      tanh        | Tanh blending (smooth)

wherein omega predictions for the viscous and inertial sublayers are blended according to the following expressions:

stepwise:

$\omega = \omega_{log} \qquad if \quad y^+ > y^+_{lam}$

$\omega = \omega_{vis} \qquad if \quad y^+ <= y^+_{lam}$

where

$\omega$	=	$\omega$ at
$\omega_{vis}$	=	$\omega$ computed by using viscous sublayer assumptions
$\omega_{log}$	=	$\omega$ computed by using inertial sublayer assumptions
	=	estimated wall-normal height of the cell centre in wall units
$y^+_{lam}$	=	estimated intersection of the viscous and inertial sublayers

max (PH:Eq. 27):

$\omega = max(\omega_{vis}, \omega_{log})$

binomial2 (ME:Eq. 15) (default):

$\omega = \sqrt{(\omega_{vis})^2 + (\omega_{log})^2}$

binomial:

$\omega = ((\omega_{vis})^n + (\omega_{log})^n)^{1/n}$

where

=

Binomial blending exponent

exponential (PH:Eq. 32):

$\omega = \omega_{vis} \exp[-\Gamma] + \omega_{log} \exp[-1/\Gamma]$

where (PH:Eq. 31)

$\Gamma$	=	Blending expression
$\Gamma$	=

tanh (KAS:Eqs. 33-34):

$\omega = \phi \omega_{b1} + (1 - \phi)\omega_{b2}$

where

$\phi$	=
$\omega_{b1}$	=	$\omega_{vis} + \omega_{log}$
$\omega_{b2}$	=	$(\omega_{vis}^{1.2} + \omega_{log}^1.2)^{1/1.2}$

G predictions for the viscous and inertial sublayers are blended in a stepwise manner, and G below $y^+_{lam}$ (i.e. in the viscous sublayer) is presumed to be zero.

Note

The coefficients Cmu, kappa, and E are obtained from the specified nutWallFunction in order to ensure that each patch possesses the same set of values for these coefficients.
The reason why binomial2 and binomial blending methods exist at the same time is to ensure the bitwise regression with the previous versions since binomial2 and binomial with n=2 will yield slightly different output due to the miniscule differences in the implementation of the basic functions (i.e. pow, sqrt, sqr).

See also

Foam::epsilonWallFunctionFvPatchScalarField

Source files

Definition at line 287 of file omegaWallFunctionFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ omegaWallFunctionFvPatchScalarField() [1/5]

omegaWallFunctionFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF
	)

Definition at line 308 of file omegaWallFunctionFvPatchScalarField.C.

Referenced by omegaWallFunctionFvPatchScalarField::clone().

Here is the caller graph for this function:

◆ omegaWallFunctionFvPatchScalarField() [2/5]

omegaWallFunctionFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Definition at line 346 of file omegaWallFunctionFvPatchScalarField.C.

References dict, Foam::endl(), dictionary::found(), dictionary::get(), IOWarningInFunction, Foam::nl, and Foam::operator==().

Here is the call graph for this function:

◆ omegaWallFunctionFvPatchScalarField() [3/5]

omegaWallFunctionFvPatchScalarField	(	const omegaWallFunctionFvPatchScalarField &	ptf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Definition at line 326 of file omegaWallFunctionFvPatchScalarField.C.

◆ omegaWallFunctionFvPatchScalarField() [4/5]

omegaWallFunctionFvPatchScalarField ( const omegaWallFunctionFvPatchScalarField & owfpsf )

Definition at line 407 of file omegaWallFunctionFvPatchScalarField.C.

◆ omegaWallFunctionFvPatchScalarField() [5/5]

omegaWallFunctionFvPatchScalarField	(	const omegaWallFunctionFvPatchScalarField &	owfpsf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Definition at line 424 of file omegaWallFunctionFvPatchScalarField.C.

◆ ~omegaWallFunctionFvPatchScalarField()

virtual ~omegaWallFunctionFvPatchScalarField ( )

virtualdefault

Member Function Documentation

◆ setMaster()

void setMaster ( )

protectedvirtual

Definition at line 48 of file omegaWallFunctionFvPatchScalarField.C.

References forAll, fvPatchField< scalar >::internalField(), omegaWallFunctionFvPatchScalarField::master(), omegaWallFunctionFvPatchScalarField::master_, omegaWallFunctionFvPatchScalarField::omega(), and omegaWallFunctionFvPatchScalarField::omegaPatch().

Here is the call graph for this function:

◆ createAveragingWeights()

void createAveragingWeights ( )

protectedvirtual

Definition at line 78 of file omegaWallFunctionFvPatchScalarField.C.

References DynamicList::append(), GeometricField::boundaryField(), polyMesh::changing(), Foam::dimless, forAll, mesh, IOobject::NO_READ, IOobject::NO_WRITE, fvPatchField::patchInternalField(), fvMesh::time(), Time::timeName(), and Foam::Zero.

Here is the call graph for this function:

◆ omegaPatch()

Foam::omegaWallFunctionFvPatchScalarField & omegaPatch ( const label patchi )

protectedvirtual

Definition at line 138 of file omegaWallFunctionFvPatchScalarField.C.

References GeometricField::boundaryField().

Referenced by omegaWallFunctionFvPatchScalarField::setMaster().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ calculateTurbulenceFields()

void calculateTurbulenceFields	(	const turbulenceModel &	turbulence,
		scalarField &	G0,
		scalarField &	omega0
	)

protectedvirtual

Definition at line 155 of file omegaWallFunctionFvPatchScalarField.C.

References omegaWallFunctionFvPatchScalarField::calculate(), fvPatch::faceCells(), forAll, Foam::constant::electromagnetic::G0, and fvPatchField::patch().

Here is the call graph for this function:

◆ calculate()

void calculate	(	const turbulenceModel &	turbulence,
		const List< scalar > &	cornerWeights,
		const fvPatch &	patch,
		scalarField &	G,
		scalarField &	omega
	)

protectedvirtual

Reimplemented in atmOmegaWallFunctionFvPatchScalarField.

Definition at line 188 of file omegaWallFunctionFvPatchScalarField.C.

References GeometricField::boundaryField(), nutWallFunctionFvPatchScalarField::Cmu(), Foam::exp(), forAll, Foam::constant::electromagnetic::G0, k, turbulenceModel::k(), nutWallFunctionFvPatchScalarField::kappa(), Foam::mag(), Foam::max(), turbulenceModel::nu(), nutWallFunctionFvPatchScalarField::nutw(), Foam::foamVersion::patch, Foam::pow(), Foam::pow025(), Foam::pow4(), fvPatchField::snGrad(), Foam::sqr(), Foam::sqrt(), Foam::tanh(), turbulenceModel::U(), y, turbulenceModel::y(), yPlus, and nutWallFunctionFvPatchScalarField::yPlusLam().

Referenced by omegaWallFunctionFvPatchScalarField::calculateTurbulenceFields().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ master()

virtual label& master ( )

inlineprotectedvirtual

Definition at line 383 of file omegaWallFunctionFvPatchScalarField.H.

References omegaWallFunctionFvPatchScalarField::master_.

Referenced by omegaWallFunctionFvPatchScalarField::setMaster().

Here is the caller graph for this function:

◆ TypeName()

TypeName ( "omegaWallFunction" )

◆ clone() [1/2]

virtual tmp<fvPatchScalarField> clone ( ) const

inlinevirtual

Reimplemented in atmOmegaWallFunctionFvPatchScalarField.

Definition at line 430 of file omegaWallFunctionFvPatchScalarField.H.

References omegaWallFunctionFvPatchScalarField::omegaWallFunctionFvPatchScalarField().

Here is the call graph for this function:

◆ clone() [2/2]

virtual tmp<fvPatchScalarField> clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Reimplemented from fixedValueFvPatchField< scalar >.

Reimplemented in atmOmegaWallFunctionFvPatchScalarField.

Definition at line 447 of file omegaWallFunctionFvPatchScalarField.H.

References omegaWallFunctionFvPatchScalarField::omegaWallFunctionFvPatchScalarField().

Here is the call graph for this function:

◆ G()

Foam::scalarField & G ( bool init = false )

Definition at line 444 of file omegaWallFunctionFvPatchScalarField.C.

References init(), and Foam::foamVersion::patch.

Here is the call graph for this function:

◆ omega()

Foam::scalarField & omega ( bool init = false )

Definition at line 463 of file omegaWallFunctionFvPatchScalarField.C.

References init(), and Foam::foamVersion::patch.

Referenced by omegaWallFunctionFvPatchScalarField::setMaster().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ updateCoeffs()

void updateCoeffs ( )

virtual

Reimplemented from fvPatchField< scalar >.

Definition at line 481 of file omegaWallFunctionFvPatchScalarField.C.

References forAll, Foam::constant::universal::G, Foam::constant::electromagnetic::G0, turbulenceModel::GName(), Foam::constant::atomic::group, IOobject::groupName(), Foam::foamVersion::patch, turbulenceModel::propertiesName, and fvPatchField::updateCoeffs().

Here is the call graph for this function:

◆ updateWeightedCoeffs()

void updateWeightedCoeffs ( const scalarField & weights )

virtual

Reimplemented from fvPatchField< scalar >.

Definition at line 527 of file omegaWallFunctionFvPatchScalarField.C.

References forAll, Foam::constant::universal::G, Foam::constant::electromagnetic::G0, turbulenceModel::GName(), Foam::constant::atomic::group, IOobject::groupName(), Foam::foamVersion::patch, turbulenceModel::propertiesName, and fvPatchField::updateCoeffs().

Here is the call graph for this function:

◆ manipulateMatrix() [1/2]

void manipulateMatrix ( fvMatrix< scalar > & matrix )

virtual

Definition at line 584 of file omegaWallFunctionFvPatchScalarField.C.

References fvPatchField::manipulateMatrix(), Foam::foamVersion::patch, and fvMatrix::setValues().

Here is the call graph for this function:

◆ manipulateMatrix() [2/2]

void manipulateMatrix	(	fvMatrix< scalar > &	matrix,
		const scalarField &	weights
	)

virtual

Definition at line 600 of file omegaWallFunctionFvPatchScalarField.C.

References DynamicList::append(), Foam::expressions::patchExpr::debug, Foam::endl(), fld, forAll, fvPatchField::manipulateMatrix(), Foam::foamVersion::patch, Foam::Pout, and fvMatrix::setValues().

Here is the call graph for this function:

◆ write()

void write ( Ostream & os ) const

virtual

Reimplemented from fixedValueFvPatchField< scalar >.

Reimplemented in atmOmegaWallFunctionFvPatchScalarField.

Definition at line 643 of file omegaWallFunctionFvPatchScalarField.C.

References os(), fixedValueFvPatchField< Type >::write(), and Ostream::writeEntry().

Here is the call graph for this function:

Member Data Documentation

◆ tolerance_

Foam::scalar tolerance_ = 1e-5

staticprotected

Definition at line 323 of file omegaWallFunctionFvPatchScalarField.H.

◆ blended_

bool blended_

protected

Definition at line 327 of file omegaWallFunctionFvPatchScalarField.H.

◆ initialised_

bool initialised_

protected

Definition at line 330 of file omegaWallFunctionFvPatchScalarField.H.

◆ master_

label master_

protected

Definition at line 333 of file omegaWallFunctionFvPatchScalarField.H.

Referenced by omegaWallFunctionFvPatchScalarField::master(), and omegaWallFunctionFvPatchScalarField::setMaster().

◆ beta1_

scalar beta1_

protected

Definition at line 336 of file omegaWallFunctionFvPatchScalarField.H.

◆ G_

scalarField G_

protected

Definition at line 339 of file omegaWallFunctionFvPatchScalarField.H.

◆ omega_

scalarField omega_

protected

Definition at line 342 of file omegaWallFunctionFvPatchScalarField.H.

◆ cornerWeights_

List<List<scalar> > cornerWeights_

protected

Definition at line 345 of file omegaWallFunctionFvPatchScalarField.H.

The documentation for this class was generated from the following files:

src/TurbulenceModels/turbulenceModels/derivedFvPatchFields/wallFunctions/omegaWallFunctions/omegaWallFunction/omegaWallFunctionFvPatchScalarField.H
src/TurbulenceModels/turbulenceModels/derivedFvPatchFields/wallFunctions/omegaWallFunctions/omegaWallFunction/omegaWallFunctionFvPatchScalarField.C

Public Member Functions

Protected Member Functions

Protected Attributes

Static Protected Attributes

Additional Inherited Members

Detailed Description

Constructor & Destructor Documentation

◆ omegaWallFunctionFvPatchScalarField() [1/5]

◆ omegaWallFunctionFvPatchScalarField() [2/5]

◆ omegaWallFunctionFvPatchScalarField() [3/5]

◆ omegaWallFunctionFvPatchScalarField() [4/5]

◆ omegaWallFunctionFvPatchScalarField() [5/5]

◆ ~omegaWallFunctionFvPatchScalarField()

Member Function Documentation

◆ setMaster()

◆ createAveragingWeights()

◆ omegaPatch()

◆ calculateTurbulenceFields()

◆ calculate()

◆ master()

◆ TypeName()

◆ clone() [1/2]

◆ clone() [2/2]

◆ G()

◆ omega()

◆ updateCoeffs()

◆ updateWeightedCoeffs()

◆ manipulateMatrix() [1/2]

◆ manipulateMatrix() [2/2]

◆ write()

Member Data Documentation

◆ tolerance_

◆ blended_

◆ initialised_

◆ master_

◆ beta1_

◆ G_

◆ omega_

◆ cornerWeights_